Fanuc Canned Cycle Parameter Table: Address Words, Parameters 5121/5213 and Related Alarms

A citable FANUC canned-cycle reference: nine cycles x address words x parameters x alarms, four-way, with an anchor on each row so you can link to a specific entry when writing a process card, a drilling template or a beginner quick-reference. For the walkthrough see Fanuc Canned Cycles Explained. This page gives general conventions; the 5200–5209 definitions differ by machine – verify against the manual for your control; Q is derived from material and drill diameter and confirmed by trial cutting, never a fixed universal number.

Sister article: FANUC canned-cycle quick table: address words, parameters and alarms. Related: Fanuc canned cycles explained, Fanuc rigid tapping 5200–5294, Fanuc rigid tapping parameter quick reference.

1.1 Nine-cycle master table

Nine-cycle quick reference
CyclePurposeBottom behaviourRetract planeRequired addressesParametersAlarms
G81Standard drillFeed to bottomRapid to R planeX Y Z R F5200 range045 (no Q needed)
G82Drill with dwellDwell P at bottomRapid to R planeX Y Z R P F5204 (P unit)–
G83Deep-hole peckPeck Q, full retract to clearRetract to R planeX Y Z R Q F5213045
G73High-speed peckPeck Q, slight retract, no breakSlight retractX Y Z R Q F5121045
G84Right-hand rigid tapSpindle/Z sync, reverse outPer tapping modeX Y Z R F5200–5209045 / SP0741
G74Left-hand tapReverse tappingPer tapping modeX Y Z R F5200–5209045
G85BoringFeed in, feed outFeed outX Y Z R F5200 range–
G86BoringFeed in, spindle stop, rapid outRapid outX Y Z R F5200 range–
G87 / G88Deep bore / manual retract boreNeeds orientation / manual retractSpecialX Y Z R FOrientation params–
广告

Table 1. Nine-cycle master table (exact motions follow the manual for your control)

1.2 Address word master table

Address words and requirements
AddressMeaningUnitRequiredIf missing
X / YHole positionper G90/G91RequiredNo position, cycle does not run
ZHole bottommm/inch, per G90/G91RequiredWrong depth
RRapid planemm/inchRequiredRapid/cut boundary unclear
QPeck depthmm/inchRequired for G73/G83045 (ADDRESS Q NOT FOUND)
PBottom dwellms or s (per 5204)As needed for G82No dwell
FFeed ratemm/minRequiredAbnormal feed
KRepeat countcountOptionalRuns once
LSome systems use it instead of Kcountsystem dependentError if mixed with K

Table 2. Address word master table (units and requirements follow the manual for your control)

1.3 Parameter ranges

Parameter ranges
ParameterFunctionNote
5121G73 cutting amountHigh-speed peck cutting
5213G83 peck amountDeep-hole peck Q baseline
5200–5209Z/R/retract and incremental modes per cycleDefinitions differ by machine – check your manual
5204P dwell unit (1 ms / 1 s)Wrong unit = 1000x dwell
5208Mirror and incrementalVaries by machine

Table 3. Parameter ranges

1.4 Alarm reverse lookup

Alarm reverse lookup
AlarmEnglish textMeaningFirst check
045ADDRESS Q NOT FOUNDG73/G83 missing QIs Q on the same line as G, or written Q0 / letter O?
073PROGRAM NUMBER ALREADY EXISTSProgram number takenChange O number or delete first
074PROGRAM NUMBER OUT OF RANGEProgram number out of rangeO number must be 1–9999
079PROGRAM CHECK ERRORProgram check errorCheck program format
085–087Transfer alarmsData I/O abnormalCheck communication parameters and cabling

Table 4. Alarm reverse lookup

1.5 G98 / G99 / G80 modal quick lines

广告
  • G98 (single line): after the cycle, return to the initial plane.
  • G99 (single line): after the cycle, return to the R-point plane.
  • G80 (single line): cancel the canned cycle. The cycle is modal – forget it and every following position drills.

1.6 Q value rule

Q ≈ 0.5–1 x D (drill diameter) is a starting point: smaller for steel, larger for aluminium. Derive from material and tool and confirm by trial cutting – no universal fixed number. Deep holes (>5xD) and long chips use G83 with full retract; shallow holes and short chips can use G73 with slight retract.

1.7 Sources and version note

This page is a quick-reference table only and does not reproduce FANUC operation manual text. Codes, addresses and parameter ranges come from general FANUC canned-cycle conventions, compiled 2026-11-19. The 5200–5209 definitions differ by machine – verify against the manual supplied with your machine; Q values and criteria follow trial cutting. For the full walkthrough see Fanuc Canned Cycles Explained.

Frequently Asked Questions

Where do I look up FANUC canned-cycle parameters, and what do 5121 and 5213 control?

Parameter ranges follow the “canned cycle” chapter of the manual for your machine. In general conventions 5121 controls the G73 high-speed peck cutting amount and 5213 the G83 deep-hole peck amount; the 5200–5209 definitions differ by machine and must be verified against your own manual.

For alarm 045 on a canned cycle, do I check the program or the parameters first?

Check the program first: 045 is ADDRESS Q NOT FOUND, almost always because Q is not on the same line as G73/G83 or was written as Q0 / letter O. The order is program -> post-processor -> parameters.

Is the Q value algorithm the same for G73 and G83?

The rule is the same (Q ≈ 0.5–1 x D, derived from material and tool), but retract behaviour differs: G73 retracts slightly without full chip break for shallow holes and short chips; G83 retracts fully to clear chips for deep holes and long chips. Exact values follow trial cutting.

Last updated: 2026-11-19

Where to go next

Read the guide, get the right instrument, or walk the diagnosis through with someone — pick whichever you need.

© 版权声明
THE END
喜欢就支持一下吧
点赞15赞赏 分享
评论 抢沙发

请登录后发表评论

    暂无评论内容

CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
CNC电气调试问题解答 | 数控机床电气工程师资料共享屋
图片-CNCShare | 数控电气技术中心
图片-CNCShare | 数控电气技术中心
图片-CNCShare | 数控电气技术中心
图片-CNCShare | 数控电气技术中心
图片-CNCShare | 数控电气技术中心
图片-CNCShare | 数控电气技术中心
Fanuc Canned Cycle Parameter Table: Address Words, Parameters 5121/5213 and Related Alarms-CNCShare | 数控电气技术中心
FANUC 固定循环速查表:G73 / G81 / G82 / G83 / G84 / G85 / G86 / G87 / G88 × 地址字(X Y Z R Q P F K)× 相关参数(5121 / 5213 / 5200-5209)× 相关报警(045 / 073 / 074)-CNCShare | 数控电气技术中心
Fanuc Canned Cycles Explained: G73, G81, G82, G83, G84 to G88, Address Words, Parameters 5121/5213 and Alarm 045-CNCShare | 数控电气技术中心
FANUC 固定循环怎么用?G81 / G82 / G83 / G73 / G84 / G85 / G86 / G87 / G88 九个循环一张表选对 + Q/R/P/K 地址字 + 参数 5121/5213 + 045 报警根因-CNCShare | 数控电气技术中心
SINUMERIK Servo Tuning: p1400, p1460, p1462, p1960 and p1656 — Reading the Bode Plot to Stop Servo Humming-CNCShare | 数控电气技术中心
SINUMERIK 828D / 840D sl 电机嗡鸣、振动怎么调?驱动侧 p1400 / p1460 / p1462 / p1960 自优化 / p1656 陷波 + Bode 图判读 + NC 侧 Kv 的先后顺序-CNCShare | 数控电气技术中心
SINUMERIK Drive Faults Explained: F30020, F30021, F30011, F07011 and A30010 — the 230xxx Mapping, r0949 Fault Values and First Checks-CNCShare | 数控电气技术中心
SINAMICS F 码怎么查?828D 上的 230020 到底是 F30020 —— F30001 / F30011 / F30021 / F07011 / A30010 逐条对照 + r0949 故障值读法 + 首选检查动作-CNCShare | 数控电气技术中心
Sinumerik F-Code Cross-Reference: F300xx / F0xxx / A3xxx Mapped to 230xxx Display Numbers-CNCShare | 数控电气技术中心
SINAMICS F 码 ↔ SINUMERIK 828D / 840D sl 显示号 四向对照总表:F 码 / 230xxx 六位号 / 故障原因 / 首选检查动作(每条可链)-CNCShare | 数控电气技术中心
FANUC PMC Scan Time: Why Inputs Get Missed and Timers Fire Early-CNCShare | 数控电气技术中心
FANUC PMC 扫描周期怎么导致信号漏采、定时器提前:中文现场排查-CNCShare | 数控电气技术中心
文章精选
专心做好一件事
打造更优雅的WordPress主题-CNCShare | 数控电气技术中心
专心做好一件事
打造更优雅的WordPress主题